如何在proe工程图的默认公差为“正-负”模式而不是“限制”模式

秋水传情

通过在***.dtl（我的工程图配置文件）中，把tol_display的值设置为yes后，同时把config.pro文件的tol_mode设置为nominal，标注出来的所有尺寸的公差模式都是“限制”，无论我如何更改config.pro中tol_mode的值，（保存-退出proe-重进proe），标注的尺寸公差模式永远都是“限制”，这是什么原因，我希望能默认为“加-减”模式，搜索论坛以前的问题，都说把tol_mode设为nominal，依这么设为何我的没有效果？（我已经把drawing_setup_file设成我工程图配置文件的路径了，更改其他项目都有效果，这说明我的工程图配置文件是有效的）
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[ 本帖最后由 yun0336wu 于 2009-10-31 12:17 编辑 ]

野火

默认就是限制模式： limits *

秋水传情

不是呀，我希望改成“加-减”的，但在config.pro中把tol_mode设置成plusminus，标出来的公差还是极限形式的。

XY226688521

不明白，看看

秋水传情

哎，无论我的选项怎么改，标注时公差默认还是限制的 好像我的config.pro文件不起作用一样，我的**.dtl文件绝对加载成功了呀，改其他项目都有效果，唯独这个公差的问题不起作用，不知道问题出在哪，要疯了。

野火

公差模式是在 config.pro 配置的，与**.dtl加载无关

野火

你是说尺寸属性里默认加减吧，那个做不到的。

fanyang95

我一般在config中都把  tol_mode    设置成   nominal，然后在dtl文件中  tol_display     设置为  yes

我认为很多尺寸不需要公差，还有些要对称公差，有些要上下标公差，索性我就不显示公差，然后在我需要显示公差时，对个体尺寸选择公差模式即可，方便些


我的dtl

drawing_text_height 3.500000
text_thickness 0.000000
text_width_factor 0.700000
broken_view_offset 3.000000
create_area_unfold_segmented YES
def_view_text_height 3.500000
def_view_text_thickness 0.000000
detail_circle_line_style PHANTOMFONT
detail_circle_note_text 详图
detail_view_circle ON
half_view_line SYMMETRY_ISO
model_display_for_new_views no_hidden
projection_type FIRST_ANGLE
show_total_unfold_seam YES
tan_edge_display_for_new_views DEFAULT
view_note STD_ANSI
view_scale_denominator 30
view_scale_format RATIO_COLON
detail_view_boundary_type CIRCLE
detail_view_scale_factor 2.000000
crossec_arrow_length 3.000000
crossec_arrow_style TAIL_ONLINE
crossec_arrow_width 1.000000
crossec_text_place ABOVE_LINE
crossec_type OLD_STYLE
cutting_line STD_ISO
cutting_line_adapt YES
cutting_line_segment 5.000000
def_xhatch_break_around_text YES
def_xhatch_break_margin_size 1.000000
draw_cosms_in_area_xsec NO
remove_cosms_from_xsecs TOTAL
show_quilts_in_total_xsecs NO
datum_point_shape CROSS
datum_point_size 1.000000
hidden_tangent_edges DEFAULT
hlr_for_datum_curves YES
hlr_for_pipe_solid_cl NO
hlr_for_threads YES
location_radius DEFAULT(2.)
mesh_surface_lines ON
ref_des_display NO
show_sym_of_suppressed_weld NO
thread_standard STD_ISO
weld_light_xsec NO
weld_solid_xsec NO
allow_3d_dimensions YES
angdim_text_orientation PARALLEL_ABOVE
associative_dimensioning YES
blank_zero_tolerance NO
chamfer_45deg_leader_style STD_ISO
chamfer_45deg_dim_text JIS
clip_diam_dimensions YES
clip_dimensions YES
clip_dim_arrow_style NONE
default_dim_elbows YES
dim_fraction_format STD
dim_leader_length 5.000000
dim_text_gap 1.200000
display_tol_by_1000 NO
draft_scale 1.000000
draw_ang_units ANG_DEG
draw_ang_unit_trail_zeros YES
dual_digits_diff 1
dual_dimensioning NO
dual_dimension_brackets YES
dual_metric_dim_show_fractions NO
dual_secondary_units INCH
iso_ordinate_delta YES
lead_trail_zeros STD_METRIC
lead_trail_zeros_scope ALL
orddim_text_orientation PARALLEL
ord_dim_standard STD_ISO
parallel_dim_placement ABOVE
radial_dimension_display STD_ASME
shrinkage_value_display PERCENT_SHRINK
symmetric_tol_display_standard STD_ASME
text_orientation PARALLEL_DIAM_HORIZ
tol_display yes
tol_text_height_factor 0.500000
tol_text_width_factor 0.600000
use_major_units NO
witness_line_delta 1.500000
witness_line_offset 1.000000
default_font font
dim_dot_box_style DEFAULT
draw_arrow_length 3.000000
draw_arrow_style FILLED
draw_arrow_width 1.000000
draw_attach_sym_height DEFAULT
draw_attach_sym_width DEFAULT
draw_dot_diameter 1.000000
leader_elbow_length 6.000000
leader_extension_font SOLIDFONT
axis_interior_clipping NO
axis_line_offset 5.000000
circle_axis_offset 3.000000
radial_pattern_axis_circle YES
asme_dtm_on_dia_dim_gtol ON_GTOL
gtol_datums STD_ISO_JIS
gtol_datum_placement_default ON_BOTTOM
gtol_dim_placement ON_BOTTOM
new_iso_set_datums YES
stacked_gtol_align NO
2d_region_columns_fit_text NO
all_holes_in_hole_table YES
dash_supp_dims_in_region YES
def_bom_balloons_attachment EDGE
def_bom_balloons_snap_lines NO
def_bom_balloons_stagger NO
def_bom_balloons_stagger_value 15.000000
def_bom_balloons_view_offset 20.000000
def_bom_balloons_edge_att_sym FILLED_DOT
def_bom_balloons_surf_att_sym INTEGRAL
min_dist_between_bom_balloons 20.000000
model_digits_in_region NO
reference_bom_balloon_text "DEFAULT"
show_cbl_term_in_region YES
sort_method_in_region DELIMITED
zero_quantity_cell_format EMPTY
draw_layer_overrides_model NO
ignore_model_layer_status YES
model_grid_balloon_display YES
model_grid_balloon_size 8.000000
model_grid_neg_prefix -
model_grid_num_dig_display 0
model_grid_offset DEFAULT
model_grid_text_orientation HORIZONTAL
model_grid_text_position CENTERED
pipe_pt_line_style DEFAULT
pipe_pt_shape CROSS
pipe_pt_size DEFAULT
show_pipe_theor_cl_pts BEND_CL
decimal_marker COMMA_FOR_METRIC_DUAL
default_pipe_bend_note NO
drawing_units MM
harn_tang_line_display NO
line_style_standard STD_ISO
max_balloon_radius 0.000000
min_balloon_radius 0.000000
node_radius DEFAULT
pos_loc_format %s%x%y, %r
sym_flip_rotated_text YES
weld_symbol_standard STD_ISO
yes_no_parameter_display TRUE_FALSE

我的config

! ==========================
!===========================
pro_unit_sys mmns
allow_anatomic_features yes
bell no
display HIDDENVIS
orientation trimetric
display_coordinate_sys YES
grid_snap NO
model_tree_start yes
spin_center_display no
menu_font 8, ARIAL, BOLD
default_font 8, ARIAL, BOLD
trail_dir E:\ptc\trail_dir
enable_absolute_accuracy YES
retain_display_memory yes
sketcher_intent_manager yes
template_solidpart E:\ptc\proeWildfire_start\solidpart.prt
template_mfgmold mmns_asm_design.asm
template_sheetmetalpart E:\ptc\proeWildfire_start\sheetmetalpart.prt
template_designasm E:\ptc\proeWildfire_start\designasm.asm

!===========================
!===========================
!***************************
! Use Windows printer manager
! as the default printer driver.
!***************************
plotter_command windows_print_manager

!===========================
! Drawing setup
!===========================
!***************************
! Use "metric.dtl" under the
! dir "d:\ptc\proe2001\text"
! as the
! standard drawing setup file.
!***************************
drawing_setup_file e:\ptc\standard\standard_config\wf_standard.dtl

!===========================
!===========================

!***************************
! F1 represents View / Default
!***************************

!***************************
! F2 represents View / Shade
!***************************

!***************************
! F3 represents
! Window / Close Window
!***************************

!***************************
! F4 represents File/Erase
!***************************

!***************************
! F5 blanks Datums
!***************************
enable_popup_help yes
nccheck_type vericut
modelcheck_enabled yes
file_open_default_folder working_directory
autobuildz_enabled yes
intf3d_ug_install_dir D:\cax\UGS\NX 3.0\UGII
tol_mode nominal
tolerance_class medium
tolerance_standard iso
pro_font_dir C:\WINDOWS\Fonts
pro_dtl_setup_dir E:\ptc\standard\standard_config
start_model_dir E:\ptc\proeWildfire_start
system_colors_file E:\ptc\standard\standard_config\syscol.scl
menu_translation yes
save_drawing_picture_file embed
pro_plot_config_dir E:\ptc\plot_config\
reserved_menu_space 0
save_display no
msg_translation yes
help_translation yes
dialog_translation yes
display_full_object_path yes
default_dec_places 3
default_object_invalid_refs prohibit
default_object_scope_setting all
fix_boundaries_on_import yes
intf3d_in_close_open_boundaries yes
linear_tol 2 0.15
multiple_skeletons_allowed yes
new_relation_ui yes
save_objects changed
set_menu_width 5
sketcher_dec_places 2
save_model_display shading_lod
shade_mfg_ref_models yes
save_bitmap none
smooth_lines yes
spin_with_part_entities yes
tol_display no
topobus_enable yes
prehighlight yes
mdo_density 7.85e-6
text_height_factor 47
def_layer layer_DATUM DATUM
def_layer layer_AXIS AIX
def_layer LAYER_CSYS CSYS
def_layer LAYER_POINT POINT
def_layer LAYER_CURVE CURVE
bom_format E:\ptc\standard\bom\yf_bom.fmt
search_path $HOME
pro_library_dir E:\ptc\ProLibs\
pro_catalog_dir E:\ptc\standard\ProLibs\
pro_material_dir E:\ptc\materials_lib
pro_symbol_dir E:\ptc\yf_symbol\
pro_group_dir E:\ptc\UDF
browser_favorite e:\ptc\project
allow_move_view_with_move yes
display_axis_tags no
drawing_file_editor editor
make_parameters_from_fmt_tables yes
pro_editor_command C:\WINDOWS\NOTEPAD.EXE
pro_format_dir E:\ptc\format
format_setup_file E:\ptc\standard\standard_config\wf_standard.dtl
pro_crosshatch_dir E:\ptc\crosshatch
pro_note_dir E:\ptc\notes
rename_drawings_with_object both
highlight_new_dims yes
parenthesize_ref_dim yes
ang_units ang_deg
use_major_units no
switch_dims_for_notes no
symbol_palette_input yes
angular_tol 2 0.10
display_dwg_tol_tags yes
restricted_gtol_dialog yes
sym_leader_orient_move_text no
display_in_adding_view default
auto_regen_views yes
force_wireframe_in_drawings no
tangent_edge_display solid
display_silhouette_edges yes
edge_display_quality very_high
save_modified_draw_models_only no
interface_quality 0
compress_output_files no
chamfer_45deg_dim_text asme/ansi
delete_after_plotting no
plot_names no
use_software_linefonts yes
dxf_out_drawing_scale yes
plotter setup
force_new_file_options_dialog yes
use_8_plotter_pens yes
pen1_line_weight 4
pen2_line_weight 2
pen3_line_weight 2
pen4_line_weight 2
pen5_line_weight 2
pen6_line_weight 2
pen7_line_weight 2
pen8_line_weight 2
todays_date_note_format %yyyy.%mm.%dd
mass_property_calculate automatic
visible_message_lines 1
pen_table_file E:\ptc\plot_config\table.pnt
plot_file_dir E:\ptc\plot_config
quick_print_plotter_config_file E:\ptc\plot_config\KONICA MINOLTA 210.pcf



! change orientation to orient z axis in top direction
x_angle -50
y_angle -20
blended_transparency NO

! location of program file
!protkdat D:\cax\ptc\pdx5\text\protk.dat
dxf_out_stroke_text all

秋水传情

原帖由 野火 于 2009-8-4 07:35 发表
你是说尺寸属性里默认加减吧，那个做不到的。

老大说对了，我就是希望尺寸属性里默认“加-减”或“象征”，反正不要默认“限制”，这如果做不到，那tol_mode的值有什么作用呢？设成“nominal或limits或plusminus”效果不都一样？

[ 本帖最后由 秋水传情 于 2009-8-4 22:32 编辑 ]

sgp0375

将系统默认的工程图尺寸公差显示模式"tol_mode"设置为基本尺寸"nominal",即当用户在工程图中启动配置文件中的公差显示模式"tol_display"为"yes"后,所有的尺寸仍然显示基本尺寸,而需要显示公差的尺寸用户可以临时编辑其属性,加上公差即可,需要注意的是此项工作必须在3D造型前设置才能生效!!!